Circumferential Slot - Slot2 - Siemens Sinumerik 840D sl Programming Manual

16.1.21

Circumferential slot - SLOT2

Programming
SLOT2(REAL RTP, REAL RFP, REAL SDIS, REAL _DP, REAL _DPR, INT NUM,
REAL AFSL, REAL WID, REAL _CPA, REAL _CPO, REAL RAD, REAL STA1, REAL
INDA, REAL FFD, REAL FFP1, REAL _MID, INT CDIR, REAL _FAL, INT VARI,
REAL _MIDF, REAL FFP2, REAL SSF, REAL _FFCP, INT _UMODE, REAL _FS,
REAL _ZFS, INT _GMODE, INT _DMODE, INT _AMODE)
Parameters
No. Param Mask Param intern
1
RP RTP
2
Z0 RFP
3
SC SDIS
4
Z1 _DP
5
_DPR
6
N NUM
7
α1
AFSL
8
W WID
9
X0 _CPA
10
Y0 _CPO
11
R RAD
12
α0
STA1
13
α2
INDA
14
FZ FFD
15
F FFP1
16
DZ _MID
17
CDIR
18
UXY _FAL
19
VARI
Job planning
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Explanation
Retraction plane (abs)
Reference point of tool axis (abs)
Safety clearance (to be added to reference point, enter without sign)
Slot depth (abs)
Slot depth (inc) with respect to Z0 (enter without sign)
Number of slots
Opening angle of the slot
Slot width
Reference point = Center point of circle, 1st axis of the plane
Reference point = Center point of circle, 2nd axis of the plane
Radius of the circle
Starting angle
Incrementing angle
Depth infeed rate
Feedrate
Maximum depth infeed
Milling direction
0 = Climbing
1 = Conventional
Finishing allowance on plane or slot edge
Machining type
UNITS:
0 = Complete machining
1 = Roughing
2 = Finishing
3 = Finishing of edge
5 = Chamfer
TENS:
0 = Intermediate positioning with G0 line
1 = Intermediate positioning on circular path
HUNDREDS: Reserved
THOUSANDS:
0 = Compatibility mode, if INDA = 0 then full circle, INDA <> 0 then pitch circle)
1 = Full circle
2 = Pitch circle
Programming cycles externally
16.1 Technology cycles
779