Contour Grooving - Cycle952 - Siemens Sinumerik 840D sl Programming Manual

16.1.36

Contour grooving - CYCLE952

Programming
CYCLE952(STRING[100] _PRG, STRING[100] _CON, STRING[100] _CONR, INT
_VARI, REAL _F, REAL _FR, REAL _RP, REAL _D, REAL _DX, REAL _DZ, REAL
_UX, REAL _UZ, REAL _U, REAL _U1, INT _BL, REAL _XD, REAL _ZD, REAL
_XA, REAL _ZA, REAL _XB, REAL _ZB, REAL _XDA, REAL _XDB, INT _N, REAL
_DP, REAL _DI, REAL _SC, INT _DN, INT _GMODE, INT _DMODE, INT _AMODE)
Parameters
Param Param
No.
Mask intern
1
PRG _PRG
2
CON _CON
3
CONR _CONR
4
_VARI
Job planning
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Explanation
Name of stock removal program
Program name from which the updated contour of the blank is read (for residual machining)
Name of program into which the updated contour for the blank (see _AMODE TEN
THOUSANDS) will be written
Machining type
UNITS: Type of stock removal
1 = Longitudinal
2 = Transverse
3 = Parallel to contour
TENS: Machining process, (see _GMODE HUNDREDS)
1 = Roughing
2 = Finishing
3 = Complete machining
HUNDREDS: Machining direction
1 = Machining direction X -
2 = Machining direction X +
3 = Machining direction Z -
4 = Machining direction Z +
THOUSANDS: Infeed direction
1 = Externally X-
2 = Internally X +
3 = Front face Z -
4 = Rear face Z +
TEN THOUSANDS: Define effect of finishing allowances
0 = Separate UX and UZ finishing allowances
1 = Finishing allowance U parallel to contour
HUNDRED THOUSANDS: Rounding
0 = Compatibility, automatic rounding
1 = With rounding at the contour
2 = Without rounding
3 = Automatic rounding
MILLION: Relief cuts
0 = Position is not evaluated during grooving, - residual and groove turning, - remainder
1 = Machine relief cuts
2 = No machining of relief cuts
TEN MILLION: Behind/in front of turning center
0 = Machining in front of the turning center
1 = reserved
Programming cycles externally
16.1 Technology cycles
815