Thread Turning - Cycle99 - Siemens Sinumerik 840D sl Programming Manual

16.1.33

Thread turning - CYCLE99

Programming
CYCLE99(REAL _SPL, REAL _SPD, REAL _FPL, REAL _FPD, REAL _APP, REAL
_ROP, REAL _TDEP, REAL _FAL, REAL _IANG, REAL _NSP, INT _NRC, INT
_NID, REAL _PIT, INT _VARI, INT _NUMTH, REAL _SDIS, REAL _MID, REAL
_GDEP, REAL _PIT1, REAL _FDEP, INT _GST, INT _GUD, REAL _IFLANK, INT
_PITA, STRING[15] _PITM, STRING[20] _PTAB, STRING[20] _PTABA, INT
_DMODE, INT _AMODE)
Parameters
Param Param
No.
Mask intern
1
Z0 _SPL
2
X0 _SPD
3
Z1 _FPL
4
X1 _FPD
5
LW/LW2 _APP
6
LR _ROP
7
H1 _TDEP
8
U _FAL
9
DP -_IANG
αP
10
α0
_NSP
11
ND _NRC
12
NN _NID
13
P _PIT
Job planning
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Explanation
Reference point (abs)
Reference point (abs, always diameter)
End point, see _AMODE (UNITS)
End point, see _AMODE (TENS)
Thread approach, see _AMODE (HUNDREDS) or
Thread run-in = thread run-out, see _AMODE (HUNDREDS)
Thread run-out
Thread depth
Finishing allowance in X and Z
Infeed slope as a distance or an angle, see _AMODE (THOUSANDS)
> 0 = Infeed on the positive side
< 0 = Infeed on the negative side
0 = Center infeed
Starting angle offset (only effective with "single start")
Number of roughing cuts, in combination with _VARI (TEN THOUSANDS)
Number of non-cuts
Pitch as a value, see _PITA
Programming cycles externally
16.1 Technology cycles
807