Circumferential Slot - Slot2 - Siemens SINUMERIK 840D Programming Manual

03.96
3
08.97
3.6

Circumferential slot - SLOT2

Programming
SLOT2 (RTP, RFP, SDIS, DP, DPR, NUM, AFSL, WID, CPA, CPO, RAD, STA1, INDA,
FFD, FFP1, MID, CDIR, FAL, VARI, MIDF, FFP2, SSF)
Parameters
RTP
real
RFP
real
SDIS
real
DP
real
DPR
real
NUM
int
AFSL
real
WID
real
CPA
real
CPO
real
RAD
real
STA1
real
INDA
real
FFD
real
FFP1
real
MID
real
CDIR
int
FAL
real
VARI
int
MIDF
real
FFP2
real
SSF
real
The cycle requires a milling cutter with an "end tooth
cutting over center" (DIN 844).
 Siemens AG 2000 All rights reserved.
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide, Cycles (PGZ) - 04.00 Edition
Retraction plane (absolute)
Reference plane (absolute)
Safety clearance (enter without sign)
Slot depth (absolute)
Slot depth relative to the reference plane (enter without sign)
Number of slots
Angle for the slot length (enter without sign)
Circumferential slot width (enter without sign)
Center point of circle, abscissa (absolute)
Center point of circle, ordinate (absolute)
Radius of circle (enter without sign)
Initial angle
Indexing angle
Feedrate for depth infeed
Feedrate for surface machining
Maximum infeed depth for infeed (enter without sign)
Milling direction for machining the circumferential slot
Value: 2 (for G2)
3 (for G3)
Final machining allowance on slot edge (enter without sign)
Type of machining
Value: 0=Complete machining
1=Roughing
2=Finishing
Maximum infeed depth for finishing
Feedrate for finishing
Speed for finishing
3.6 Circumferential slot - SLOT2
Milling Cycles
3
3-127