Siemens SINUMERIK 840D sl Programming Manual page 209

Workpiece probe 1, used as tool T9, D1, is
to be used.
The probe is already calibrated. Arrays for
workpiece probe 1: _WP[0, ...]
The following is entered under T9, D1 in
the tool offset memory:
Tool type (DP1):
Length 1 - geometry (DP3):
Radius - geometry (DP6):
Length 1 (L1) must refer to the center of
the probe ball (_CBIT[14]=0), as for
calibration.
Careful when positioning! Radius R in
length (L1) is ignored.
%_N_ZO_DETERMINING_1_MPF
N10 G54 G17 G90 T9 D1
N20 M6
N30 G0 G90 X-20 Y25
N40 Z10
N60_TSA=6 _PRNUM=1 _VMS=0 _NMSP=1
_FA=4
N61 _MVAR=100 _SETVAL=0 _MA=1 _KNUM=1
_EVNUM=10
N70 CYCLE978
N80 G0 X-20
N90 Y-20
N100 X22
N110 _EVNUM=11 _MA=2
N120 CYCLE978
N130 G54
N140 G0 Y-20
N150 Z50
N160 X-40 Y80
N200 M2
Measuring cycles
Programming Manual, Release 04/2006, 6FC5398-4BP10-0BA0
Measuring Cycles for Milling and Machining Centers
5.5 CYCLE978 workpiece: Measuring a surface parallel to the axis
710
L1 = 50.000
R = 3.000
;ZO, select tool as probe ...
;Insert probe,
;activate tool offset
;Position probe in X/Y plane in front of
;measuring surface
;Position probe at measuring height
;Set parameters for measuring cycle call
;Measuring cycle for ZO determination in
axis
;Retract in X axis
;Position in Y axis
;Position in X axis
;Set parameters for measuring cycle call
;ZO determination in Y axis
;Repeat call of ZO G54
;This activates the changes!
;Retract in Y axis
;Retract in Z axis
;Retract in X/Y
;End of program
X
5-75