Slots On A Circle - Slot1 - Siemens SINUMERIK 840D Programming Manual
Cycles
Hide thumbs
Also See for SINUMERIK 840D:
- Function manual (920 pages) ,
- Diagnostics manual (714 pages) ,
- Operating turning (713 pages)
Table of Contents
Advertisement
3
12.97
04.00
3.5
Slots on a circle – SLOT1
Programming
SLOT1 (RTP, RFP, SDIS, DP, DPR, NUM, LENG, WID, CPA, CPO, RAD, STA1, INDA,
FFD, FFP1, MID, CDIR, FAL, VARI, MIDF, FFP2, SSF, _FALD, _STA2)
Parameters
real
RTP
real
RFP
real
SDIS
real
DP
real
DPR
int
NUM
real
LENG
real
WID
real
CPA
real
CPO
real
RAD
real
STA1
real
INDA
real
FFD
real
FFP1
real
MID
int
CDIR
real
FAL
int
VARI
real
MIDF
real
FFP2
© Siemens AG, 2002. All rights reserved
SINUMERIK 840D/840Di/810D Programming Guide Cycles (PGZ) – 11.02 Edition
Retraction plane (absolute)
Reference plane (absolute)
Safety distance (enter without sign)
Slot depth (absolute)
Slot depth relative to the reference plane (enter without sign)
Number of slots
Slot length (enter without sign)
Slot width (enter without sign)
Center point of circle, abscissa (absolute)
Center point of circle, ordinate (absolute)
Radius of circle (enter without sign)
Initial angle
Indexing angle
Feedrate for depth infeed
Feedrate for surface machining
Maximum infeed depth for infeed (enter without sign)
Milling direction for machining the slot
Value: 0...Down-cut milling (as spindle rotation)
1...Up-cut milling
2...with G2 (independent of spindle direction)
3...with G3
Final machining allowance on slot edge (enter without sign)
Machining type (enter without sign)
UNITS DIGIT:
Value: 0...Complete machining
1...Roughing
2...Finishing
TENS DIGIT:
Value: 0...Perpendicular with G0
1...Perpendicular with G1
3...Oscillation with G1
Maximum infeed depth for finishing
Feedrate for finishing
3.5 Slots on a circle – SLOT1
3
Milling Cycles
3-135
Hide quick links:
Advertisement
Table of Contents
