Feedrate Related Functions; Feedrate Programming Units (G93/G94/G95); Cnc 8070 - Fagor CNC 8070 Programming Manual

5.2

Feedrate related functions

5.2.1

Feedrate programming units (G93/G94/G95)

G94
G95
G93
The functions related to programming units permit selecting whether
mm/minute (inches/minute) or mm/revolution (inches/rev.) are
programmed or, instead, the time the axes will take to reach their
target position.
Programming
The functions related to programming units are:
G94 Feedrate in millimeters/minute (inches/minute).
G95 Feedrate in millimeters/revolution (inches/revolution).
G93 Machining time in seconds.
These functions may be programmed anywhere in the program and
they don't have to go alone in the block.
If the moving axis is rotary, the programming units will be in degrees
instead of millimeters or inches as follows:
Linear axes
G94 millimeters (inches)/minute
G95 millimeters (inches)/revolution
G93 seconds
Feedrate in millimeters/minute (inches/minute).
After executing G94, the CNC inter prets that the feedrates
programmed with the "F" code are in millimeters/minute (inches/
minute). If the moving axis is rotary, the CNC interprets that the
programmed feedrate is in degrees/minute.
Feedrate in millimeters/revolution (inches/revolution)
After executing G95, the CNC inter prets that the feedrates
programmed with the "F" code are in mm/rev (inches/rev) of the
master spindle of the channel. If the moving axis is rotary, the CNC
interprets that the programmed feedrate is in degrees/revolution.
This function does not affect the movements in G00 which are always
executed in millimeters/minute (inches/minute).
Machining time in seconds
After executing G93, the CNC interprets that the movements must be
carried out in the time period (seconds) indicated by the "F" code.
This function does not affect the movements in G00 which are always
executed in millimeters/minute (inches/minute).
Programming manual
Rotary axes
degrees/minute
degrees/revolution
seconds
5.

CNC 8070

(S V02.0 )
OFT X
57